Independent CNC repair and technical reference Contact

FANUC 31i-B S618: separate G37 licensing, H-number and measurement-signal alarms

Published Updated

G37 changes a tool offset as well as measuring a position. Separate PS0010 from PS0080, PS0081 and PS0082 on the specified 31i-B system.

Contents
  1. A working probe does not establish G37 availability
  2. Scope and authorized installation
  3. Identify the offset that will change
  4. Four alarms, different checks
  5. Separate signal faults from coordinate errors
  6. Sources and limits

A working probe does not establish G37 availability

A probe triggering an input does not prove that the CNC has automatic tool length measurement. G37 also updates compensation, so diagnosis must prevent both unexpected motion and an incorrect result being written to the offset table.

Scope and authorized installation

The 2013 FANUC catalogue lists A02B-0327-S618 for 31i-B automatic tool length measurement on machining centers/automatic tool offset on lathes. This article covers machining-center G37 using B-64484EN-2/03 and B-64485EN/01. The suffixes are manual editions, not software revisions. No minimum software revision was verified; do not transfer the order code to Plus. Before adding it, ask FANUC or the builder to check the complete model, serial number, software series/revision and option record, then perform authorized installation and acceptance. The measuring device, wiring/interface, builder configuration and license are separate requirements. Changing measurement parameters does not purchase or activate an option.

Identify the offset that will change

Specify H before G37, in a separate block, and give the measurement position in absolute coordinates. Measurement and programming must use the same work coordinate system. Motion changes from rapid approach to measurement feed and stops on the arrival signal. No executable coordinates are supplied here; do not use a contact test to check licensing. Depending on offset memory A/B/C, the updated item is the offset, wear offset or H-code wear offset, not invariably geometric tool length.

Four alarms, different checks

PS0010, IMPROPER G-CODE: the series rules include a missing corresponding option as well as an unusable G code. A rejected G37 therefore calls for checks of licensing and code applicability, not an immediate S618 diagnosis. PS0081, G37 OFFSET NO. UNASSIGNED: no prior H number. PS0082, G37 SPECIFIED WITH H CODE: H and G37 share a block. PS0080, G37 MEASURING POSITION REACHED SIGNAL IS NOT PROPERLY INPUT: arrival is too early or absent within the permitted range. That is a measurement/signal condition, not proof of missing licensing.

Separate signal faults from coordinate errors

Consider PS0080 after replacing a measuring device: this is an analytical scenario, not a repair report. Preserve the failing block, modes, H number and pre-measurement offset. Qualified personnel should first check the device and builder-defined input safely without motion, then compare the measurement position, active coordinates and triggering range. Do not widen the range to hide a coordinate or wiring error. Before retesting, check approach clearance and stopping capability using the builder procedure; afterwards verify the exact offset item and value that changed. Alarm clearance alone does not validate measurement.

Sources and limits

These are third-party mirrors of manufacturer documents. No machine test or machine-specific installation procedure was verified; FANUC or the builder must confirm applicability and acceptance conditions.

Related technical articles

FANUC 31i-B J919: why G54.1 P48 works but P49 can raise PS0030FANUC 31i-B R553: why G53.2 still needs a feed-mode checkFANUC 0i-TD J819: diagnosing alarm 0028 on a three-axis G02/G03 block